Turn the sketch into a solid

Turn the sketch into a solid — guided practice

Pad a base and remove a through-hole.

Open the constrained base. Target thickness 6 mm; through-hole diameter 8 mm centered at x=10, y=15 mm.

1. 1. Add depth

   Close sketch editing, select the base sketch, choose Pad and enter 6 mm. Confirm. Use the axonometric view to inspect.

   You should see: A 60×30×6 mm solid appears.

   A closed sketch plus a depth defines a volume.

2. 2. Locate the hole

   Clear any face selection. With the Body active, choose Create sketch and select the XY plane, the same plane used for the base. Draw a circle, then constrain its radius to 4 mm. Select its center point and apply horizontal distance 10 mm and vertical distance 15 mm from the sketch origin. If the Pad hides the sketch, select Pad in the tree and press Space to hide it temporarily. Confirm the sketch is fully constrained.

   You should see: The circle is fixed at (10, 15) on the base XY plane, with radius 4 mm.

   A circle needs both size and position constraints.

3. 3. Cut through

   Close the circle sketch, select it and choose Pocket. Set Type to Through all and enable Reversed so the cut travels from the XY plane upward through the Pad in positive Z. Inspect the preview, then confirm. Show the final Pocket and hide earlier features.

   You should see: A circular opening cuts through the complete 6 mm thickness.

   Through all expresses intent even if thickness changes.

4. 4. Inspect the result

   Rotate to see both openings. Hide earlier features if they obscure the final Pocket. Save and record the bounding dimensions.

   You should see: One solid body remains with a circular opening; dimensions are 60×30×6.

   A visible circle on a surface is not proof of a through-cut.